Okuma Alarm-B 2506 Tool center point control not possible
Specified Tool center point control operation was illegal.
Object
SYSTEM
Character-string
None
Code
1->Tool center point control instruction was executed while not Y axis mode, or Coordinate system conversion(G136,G137).
2->Tool center point control instruction was executed while C-axis not connection mode.
3->Tool center point control instruction was executed while B-axis not connection mode.
4->When instructing in the tool center point control insertion, positional specification of all axes (X,Y,Z,B,C) by absolute coordinate (G90) is not done.
5->Tool center point control instruction was executed while in the sending modes other than G00, G01, G02, and G03.
6->Tool center point control instruction was executed while tool correction number improper(0 or uninstruction).
7->Tool center point control instruction was executed while fixed cycle(G71-G74,G178-G192).
8->Tool center point control instruction was executed while in the nose-R compensation mode(G41,G42), or compensation of length of tool (G52,G158,G159).
9->Tool center point control instruction was executed while inverse time mode(G93), or rev/min mode(G95).
10->Tool center point control instruction was executed while droop ON.
11->Tool center point control instruction was executed while LAP cycle(G80-G88).11->Tool center point control instruction was executed while LAP cycle(G80-G88).
12->Tool center point control instruction was executed while tool retraction interruption mode.
13->Tool center point control instruction was executed while slant process mode.
14->Tool center point control instruction was executed while Outline processing mode(G155).
15->Tool center point control instruction was executed while W axis overlay-control mode(G117), or W axis control mode(G145).
16->Tool center point control instruction was executed while Early check control.
17->Tool center point control instruction was executed while X axis mirror image coordinate system.
18->Tool center point control instruction was executed while Parallel shift(G11) or Rotational shift(G217) of coordinate instruction.
19->When the tailstock is connected, or the steady rest was unclamped, the Tool center point control instruction was executed.
20->The TRIC invalid G-code instruction(TRIC auto OFF) and “tool center point control instruction mode” in the same block.
21->The sequence carriage return instruction in the Tool center point control instruction mode was done.
22->Tool center point control instruction was executed while performed by the 2nd spindle.
101->Circular command(G02,G03) including rotation axis(BorC) was executed while tool center point control mode.
102->Sending modes other than G00, G01, G02, and G03 was executed while tool center point control mode.
103->Fixed cycle(G71-G74,G178-G192) was executed while tool center point control mode.
104->Chamfering cycle command(G75,G76) was executed while tool center point control mode.
105->Zero-shift instruction(G50), or spindle max revolution (G50) was executed while tool center point control mode.
106->Nose-R compensation mode(G40-G42), or compensation of length of tool (G52,G158-G160) was executed while tool center point control mode.
107->Inverse time command(G93), or rev/min command(G95) was executed while tool center point control mode.
108->Constant Surface command(G96,G97), or constant surface control saddle command(G110,G111) was executed while tool center point control mode.
109->Droop command(G64,G65) was executed while tool center point control mode.
110->Lap cycle command(G80-G88) was executed while tool center point control mode.
111->Tow-along tailstock positioning cycle, or tow-along steady rest positioning cycle was executed while tool center point control mode.
112->Y axis mode(G138), or Coordinate system conversion (G136,G137) was executed while tool center point control mode.
113->Tool retraction interruption mode(G241-G243) was executed while tool center point control mode.
114->Spindle mode(G140,G141) was executed while tool center point control mode.
115->Torque skip command(G22) was executed while tool center point control mode.
116->Synchronized tapping command(G36,G37) was executed while tool center point control mode.
117->The slant process mode IN/OUT command(G126,G127) was executed while tool center point control mode.
118->Outline processing mode(G155) was executed while tool center point control mode.
119->B-axis mode IN/OUT command(G148,G149) was executed while tool center point control mode.
120->Coordinate instruction command(G15,G16) was executed while tool center point control mode.
121->W axis overlay-control mode(G116,G117), or W axis control mode(G144,G145) was executed while tool center point control mode.
122->C-axis multi rev mode(G120,G121) was executed while tool center point control mode.
123->Early check control(G98,G99) was executed while tool center point control mode.
124->X axis mirror image coordinate command(G104,G105) was executed while tool center point control mode.
125->CASCME(G201),CASCTL(G204) command was executed while tool center point control mode.
126->Spindle rev command(S command) was executed while tool center point control mode.
127->Turret indexing command(T command) was executed while tool center point control mode.
128->Instruction(M06,MG,MT,MTM,MTS,MGS) related to ATC was executed while tool center point control mode.
129->C-axis connect command(M109,M110), or C-axis clamp/unclamp command(M146,M147) was executed while tool center point control mode.
130->C-axis synchronous command(M888-M890) was executed while tool center point control mode.
131->B-axis clamp/unclamp command(M146,M147) was executed while tool center point control mode.
132->Anti-crash interference detection release (M866,M867) was executed while tool center point control mode.
133->Interrupt program function(M940-M945) was executed while tool center point control mode.
134->Writing by system variable to “zero offset, zero shift, and tool offset” was executed while tool center point control mode.
135->P-Code instruction was executed while tool center point control mode.
Probable Faulty Locations
Part program error.
Measures to Take
place applicable to above-mentioned code is modified.